
4. DESCRIPTION OF PARAMETERS
B–63610EN/01
44
1020 Program axis name for each axis
[Data type] Byte axis
Set the program axis name for each controlled axis, using one of the values
listed in the following table:
Axis
name
Setting
Axis
name
Setting
Axis
name
Setting
Axis
name
Setting
X 88 U 85 A 65 E 69
Y 89 V 86 B 66
Z 90 W 87 C 67
NOTE
1 With the T series, when G code system A is used, neither U,
V, nor W can be used as an axis name. Only when G code
system B or C is used, U, V, and W can be used as axis
names.
2 The same axis name cannot be assigned to more than one
axis.
3 When the secondary auxiliary function (option) is provided,
the address used by the secondary auxiliary function
(address B with the T series or, with the M series, the address
specified in parameter No.3460) cannot be used as an axis
name.
4 With the T series, when address C or A is used for
chamfering, corner rounding, or direct drawing dimension
programming (when the CCR parameter (bit 4 of parameter
No.3405) is set to 1), addresses C or A cannot be used as
an axis name.
5 Only with the T series, address E can be used as an axis
name. Address E cannot be used with the M series. When
address E is used as an axis name, note the following:
– When G code system A is used, address E is always
assigned to an absolute command.
– When an equal–lead threading command (G32) is issued
in the Series 10/11 command format, address E cannot be
used to specify the thread lead. Use address F to specify
the thread lead.
1022 Setting of each axis in the basic coordinate system
NOTE
When this parameter is set, power must be turned off before
operation is continued.
[Data type] Byte axis
To determine the following planes used for circular interpolation, cutter
compensation C (for the M series), tool nose radius compensation (for the
T series), etc., each control axis is set to one of the basic three axes X, Y,
and Z, or an axis parallel to the X, Y, or Z axis.